Anilam 4200T Setup guide

4200T CNC Control
Training Guide

Bookmarks Navigation Instructions
Follow bookmarks at the left side of
the page to navigate to desired topic
Click plus and minus symbols to expand
and compress menu display

4200T CNC Control
Training Guide

Turning the Control ON
1
After the control has been turned ON press F10 to continue.
Then press ENTER to select CNC mode.
F10

Main Areas of the Display
2
Command line
for MANUAL (MDI)
instructions
Active G and M codes
Position relative to machine home
Position relative to part zero
TOOL information
HELP Menu
LOOP, DWELL Counters
SPINDLE / FEED
Displays
Target or position to reach
Distance to go to reach target
Fixture Offset Indicator
PARTS Counter
PART Timer
Selected Program

Alternative Display - Function Keys
3
The Function (or F keys) activate the Mode shown directly above on the Display screen.
The meaning of F keys change, depending upon what Mode of operation is selected.
Example: With the AUTO Mode selected the F keys have the following meanings, shown below
Position relative to Part Zero Distance to go to reach Target
F1 F9 F2 F3 F4 F7F5 F8F6 F10
The Large Position Displays can be toggled by pressing and when in
the MANUAL Mode.
When in AUTO or SINGLE STEP Modes press only.
B
B

6.
Alfa -Numeric key board
Note :-Most used key are yellow . Most key also double functions , the
shift key is use to use secondary functions.
D
A C D
C
B
FGH
IKLJ
MOPN
QSTR
UWV
X8 97
Y
5 6
4Z
23 1
0
<
{$
Clear key
Enter key
Cursor keys
Space key
Shift key
>^
[] !
~@
}
_‘/
?:
%“
|;/
( ) #
*
&
=
‘
...
.

MANUAL MOVES
4
In MANUAL mode moves can be made in 3 different ways
MOVING WITH HANDWHEELS
1) Activate the handwheel(s) by pressing
2) Turn the jog mode selector switch on the MANUAL PANEL to 100, 10 or 1
to select the feedrate required (100=fast, 10=medium, 1=slow)
MOVING WITH JOG MOVEMENTS
1) Turn the jog mode selector switch on the MANUAL PANEL to 100, 10, 1, FEED or
RAPID
2) Select the axis to move with the AXIS SELECTOR switch at the MANUAL PANEL
3) Press the or the key to move in the desired direction.
_
+
HandWl

5
MOVING WITH COMMANDS
Type commands as needed and press the START button located on the
MANUAL PANEL
EXAMPLE:
Type: G0 G90 Z10 and press Start Z axis goes to Z10 in ABS and RAPID
EXAMPLE:
Type G97 S1000 M3 and press START to start the spindle at a fixed 1000
rpm.
MOST COMMON COMMANDS TO REMEMBER:
G1 Fxxx: Feed Rate in Inch per minute / Inch per rev. (mm/min or mm/revolutions)
G0: Rapid
G90: Absolute co-ordinate system
G91: Incremental co-ordinate system
G94: Feed Rate in Inch per minute (mm per minute)
G95: Feed Rate in Inch per revolution (mm per revolution
G96 Sxxx: Constant surface speed in Feet / Miinute (Meters / Minute)
G97 Sxxxx Spindle Speed in direct RPM
M41 or M42 or M43 or M44 Spindle speed gear selection
M3: Spindle forward
M4: Spindle reverse
M5: Spindle Stop
M8: Coolant ON
M9: Coolant OFF

6
CALIBRATING TOOLS
Calibrating The Z Axis
1) Access the Tool table by pressing F9 TOOL in manual mode
2) Move the Tool to the face of the part (using either the
Handwheels or Jog keys) and make a skim cut
F9
3) Without moving the Tool in the Z axis, Press F8 Calib Z Calib Z
TOOL

7
CALIBRATING TOOLS
Calibrating The X Axis
1) Access the Tool table by pressing F9 TOOL in manual mode
2) Move the Tool to the diameter of the part (using either
Handwheels or Jog keys) and make a skim cut
F9
3) Without moving the Tool in the X axis, Press F7 Calib X
4) Measure and enter the diameter of the part and Press Enter………………...
Calib X
TOOL

CALIBRATING TOOLS
4) Enter the remaining information, move the cursor to RADIUS and enter
the value of the tool nose radius
5) To enter the Location code of the tool, Press:
Use the arrow Keys to
select the the type of tool to
be used and press Enter
Repeat the procedure for additional tools without leaving the tool page .
Press when finished.
To use the Tool, mount it on the Tool Post and activate the Tool call
command:
Example:
Type: T 1 to activate TOOL 1 settings.
8
F10
F2
L-CODE
EXIT

A program must be created, then Selected and finally edited
9
CREATING A PROGRAM
Press Enter to enter the program in the
directory
Type the program name (Maximum 8
letters/numbers)
Then press
F2
F4
4.5"
4.05"
4.00"
0.05"x 45 Deg. Chamfer
0.10"x 45 Deg. Chamfer
TOOLS REQUIRED
OPERATION No.1
TOOL No.2
O.D. THREAD
TOOL No.1
ROUGH TURN
3.00" x 10 TPI
3.50"
EDIT
PROGRAM CREATE
F2

PART PROGRAM
The program can be typed directly in the editor or through the interactive HELP menu.
Use help when in doubt about what function to use or the meaning of it’s parameters.
To use HELP press :
Example: Use HELP for the threading cycle in the program
10
F1
G70 G90 G0 X0 Z0 T0 *INCH, ABSOLUTE, RAPID X Z, TOOL 0
M43 *HIGH SPINDLE RANGE
G24 S1600 *RPM LIMIT WITH CONSTANT SURFACE SPEED
T1 *CALL TOOL NO.1 (ROUGH/FINISH FACE/TURN TOOL)
G96 S400 *400 SURFACE FEET PER MINUTE
X4.7 Z0 M3 *RAPID POSITION TO FACE OFF, SPINDLE FORWARD
M8 *COOLANT ON
G1 X-.065 G95 F.007 *FACE OFF AT 0.007" INCH PER REV.
G0 X4.5 Z.1 *RAPID POSITION FOR AREA CLEAR. CYCLE
G73 W10 A.1 R.02 S.005 C1 B1 J.015 K.008 *AREA CLEAR. CYCLE
G0 X0 Z0 T0 M9 *RAPID TO TOOL CHANGE POSITION, COOLANT OFF
M5 *SPINDLE STOP
T2 *CALL TOOL NO.2 (THREADING TOOL)
M42 *MID SPINDLE RANGE
G97 S500 *500 RPM
X3.2 Z.5 M3 G95 F.04 *RAPID POSN FOR THD CYCLE, SET FEED 0.04" PER REV
M8 *COOLANT ON
G83 E10 Z-4 C-0.015 S2 R-0.1 *THREADING CANNED CYCLE
G0 X0 Z0 T0 M9 *RAPID TO TOOL CHANGE POSITION, COOLANT OFF
M5 *SPINDLE OFF
M2 *END OF MAIN PROGRAM
O10 *SUB-PROGRAM NO.10 (OD PROFILE)
G0 X2.6 Z.1 *START POSITION OF FINISH PROFILE
G1 X3 Z-.1 *CHAMFER 3" DIAMETER
Z-4 *TURN 3" DIAMETER
X4.4 *FACE OUT TO 4.4" DIA.
X4.5 Z-4.05 *CHAMFER 4.5" DIAMETER
M99 *END OF SUB-PROGRAM
HELP

11
Select Threading by pressing the key
Followed by for the Uni directional threading cycle G83
2
)
7
&

12
Please note
1) All dimensions are relative to the current position of the tool. The tool MUST be
programmed in the correct position before using this function, in particular, it must be
0.1” (2mm) clear of the diameter to be machined (add 0.2” (4mm) to the diameter to
be machined).
2) All distances are INCREMENTAL. Negative signs must be used in case of an OD
thread.
3) Programming (TPI) or (LEAD), LENGTH, FIRST CUT is mandatory. The rest of
the data is optional. Thread depth is calculated by the control.
4) When all the necessary data has been given press F10 EXIT to save the line and
leave HELP. Or press F8 ACCEPT to save the line and remain in the HELP mode

Draw graphics shows a graphical representation of all programmed moves.
1) To DRAW a program the control must be in the page.
2) Hi-lite the program name to be drawn using the arrow keys……………
3) Press to access the Draw screen
4) Press to Draw the program
5) To resize or arrange the drawn program press and
select FIT or WINDOW or HALF etc. from the menu using the arrow
keys.
EXAMPLE: Hi-LIte WINDOW, press ENTER. Use the arrow keys to
move the zoom box to the required location. Use the or
keys to increase or decrease the size of the box (the graphics will draw the content
of the box).
Press to redraw the content of the box.
To Exit the Draw mode press
13
DRAW GRAPHICS
CompresExpand
Enter
Exit
Display
Run
Draw
Program

TO RUN PART
14
After ensuring the program graphics correspond to the desired tool path:
- Exit the Editor
- verify the program is SELECTED
- then leave the program page returning into MANUAL mode
- Ensure the SERVOS are turned ON.
- As a precaution turn the FEED OVERRIDE button to 0%
Then Press:
Allow the machine to move by turning the FEED OVERRIDE gradually clockwise
until the tool speed is satisfactory. Do not hesitate to turn it back to 0% to stop it again.
Or press to stop the movement of the machine
F6
% FEED
% FEED
AUTO
DISCLAIMER
Anilam accepts no responsibility for accident, injury, loss or damage to
equipment arising from use or misuse of this presentation.
Anilam’s policy of continued development means that product operatio,
features and capabilities may alter without notice.
REMEMBER MACHINE TOOLS CAN BE DANGEROUS !!!
IF IN DOUBT ASK !!!

15
THE SHAPE EDITOR :
- The shape editor will create subprograms that can be used in the main program:
- A main program must be created before using the shape editor.
- Hi-Lite the created program prior to entering the shape editor.
- Geometry can be used to assist in the creation of the a shape.
Line tool
Arc tool
Geometry tool
Corner radius
Corner Chamfer
Chaining tool
Allows the creation of a
shape Press ENTER to
define a starting point.
Also allows to reverse an
ARC
Once a Shape has been created, Back / Forw
allows moving the shape cursor to places where
it needs to be modified
Used to size the display

Shape Editing Tools
Line tool is selected
Z Move (M to toggle INC or ABS move)
X Move (M to toggle INC or ABS move)
X & Z Move combined (M to toggle INC or ABS move)
Move a distance R (radius) and angle A. (INC movement)
Move to Z position at an angle
Move to Z position at an angle
Arc tool is selected Press ENTER to change ARC direction before selecting an ICON
Arc defined by an endpoint and a centre
Arc defined by an end point and a radius
Arc defined by a centre and an angle
Arc tangent to a line at a radius
Line from pointer at an angle followed by tangent arc.
Arc defined by end point and radius.
Arc from pointer followed by a line.
Arc defined by end point and radius.
Line defined by endpoint and angle
16