Fagor CNC 8055 T User guide

REF. 1010
8055 T
Examples manual
CNC

This product uses the following source code, subject to the terms of the GPL license. The applications busybox V0.60.2;
dosfstools V2.9; linux-ftpd V0.17; ppp V2.4.0; utelnet V0.1.1. The librarygrx V2.4.4. The linux kernel V2.4.4. The linux boot
ppcboot V1.1.3. If you would like to have a CD copy of this source code sent to you, send 10 Euros to Fagor Automation
for shipping and handling.
All rights reserved. No part of this documentation may be transmitted,
transcribed, stored in a backup device or translated into another language
without Fagor Automation’s consent. Unauthorized copying or distributing of this
software is prohibited.
The information described in this manual may be changed due to technical
modifications. Fagor Automation reserves the right to make any changes to the
contents of this manual without prior notice.
All the trade marks appearing in the manual belong to the corresponding owners.
The use of these marks by third parties for their own purpose could violate the
rights of the owners.
It is possible that CNC can execute more functions than those described in its
associated documentation; however, Fagor Automation does not guarantee the
validity of those applications. Therefore, except under the express permission
from Fagor Automation, any CNC application that is not described in the
documentation must be considered as "impossible". In any case, Fagor
Automation shall not be held responsible for any personal injuries or physical
damage caused or suffered by the CNC if it is used in any way other than as
explained in the related documentation.
The content of this manual and its validity for the product described here has been
verified. Even so, involuntary errors are possible, thus no absolute match is
guaranteed. Anyway, the contents of the manual is periodically checked making
and including the necessary corrections in a future edition. We appreciate your
suggestions for improvement.
The examples described in this manual are for learning purposes. Before using
them in industrial applications, they must be properly adapted making sure that
the safety regulations are fully met.

INDEX
Tools ................................................................................................... 1
Tool calibration ................................................................................. 2
General examples ............................................................................ 5
Canned cycles ................................................................................ 11
«C» axis programming..................................................................33
Profile Editor....................................................................................37
User screen customizing programs........................................... 43
The cutting speeds and feedrates appearing in this manual are only approximate,
they may vary depending on the material of the part and the tools used. When
machining one of the parts of these examples, use the speeds recommended by
the tool manufacturer.
The tool number will also be different depending on the machine.
========= 0 ========
Theinformationdescribedin this manual maybesubjectto variations due totechnical
modifications.
FAGOR AUTOMATION, S.Coop. Ltda. reserves the right to modify the contents of
the manual without prior notice.
WARNING

EXAMPLE MANUAL 1
TOOLS
List of tools used in these examples:

2 EXAMPLE MANUAL
TOOL CALIBRATION
ExampleofhowtocalibratetoolT2using a part of known dimenstions
(diameter: 60 mm, length: 100 mm).
Note: The X axis operates in diameter.

EXAMPLE MANUAL 3
Calibrating procedure
1. Edit the tool and tool offset tables with all the data known for each tool.
Tool table: T2 D2 F0 N0 R0
Tool offset table: D2 X0 Z0 R0.4 F3 I0 K0
Tool geometry table T2 NOSEA 60 NOSEW 7 CUTA 100
2. Select the tool and tool offset to be calibrated.
Press the softkey sequence: [Main menu] [JOG] [MDI] T2 D2
3. Select the tool calibration mode and do it along the X axis.
- Press the softkey sequence: [Main menu] [JOG] [Calibration] [+] [X]
- The CNC requests: Preset the X axis:
- Enter tool diameter 60 [Enter]
- The CNC shows the text Tool calibration.
- Move the tool with the JOG keys until touching the part.
- Press the softkey: [Load X axis]
- The CNC shows the text Offset updated.
4. Calibrate the tool along the Z axis.
- Press the softkey: [Z]
- The CNC requests: Preset the Z axis:
- Enter tool length 100 [Enter]
- The CNC shows the text Tool calibration.
- Move the tool with the JOG keys until touching the part.
- Press the softkey: [Load X axis]
- The CNC shows the text Offset updated.
If accessing the tool offset table next ...
Press the softkey sequence: [Main menu] [Tables] [Tool offsets]
... Offset D2 will show, for example, the following values:
D 2 X 57.456 Z 29.312 R 0.4 F 3 I 0 K 0
Note: The values shown by the “X” field are always in radius.

4 EXAMPLE MANUAL
User Notes:

5
Programming examples:
General examples
8055T
Zero offset. .............................................................................................. 6
Programming in absolute (G90) and incremental (G91) coordinates. ............. 7
Programming of arcs (G02/G03). (Programming in radius)............................ 8
Programming of arcs (G02/G03). (Programming in diameters) ...................... 9
Tangential entry/exit (G37/G38) and corner rounding(G36) with tool radius
compensation (G40/G41/G42). ........................................................... 10

6 EXAMPLE MANUAL
Zero offset.
This example shows two ways to do this operation: manual mode and by program. Both methods use zero offset
G54.
Manual mode:
1. Select the zero offset table.
Press the sequence of keys and softkeys: [Main menu] [Tables] [Zero offsets]
2. Edit the table for zero offset G54.
Press the sequence of keys and softkeys: [Edit] G54 X0 Z120 [Enter]
3. Select zero offset G54.
Press the sequence of keys and softkeys: [Main menu] [JOG] [MDI] G54
By program:
One of the following methods must be used.
-Execute, in MDI mode, the following program blocks and then execute the part-program.
-Edit a program with the following blocks and execute it before the part-program.
-Include the following blocks at the beginning of the machining program.
Program blocks.
(ORGX54=0, ORGZ54=120) .....................Assigns the values X0 Z120 to the G54 zero offset table.
G54 ...........................................................Selects and applies zero offset G54.
Being the Machine Zero point (home: 0.0), the face of the part, point (120,0) is going to be the new Part Zero.

EXAMPLE MANUAL 7
Programming in absolute (G90) and incremental (G91) coordinates.
Programming in radius
Absolute coordinates (G90)
G90 G95 G96 F0.15 S180 T2 D2 M4 M41
G0 X50 Z100
G1 X0 Z80 .................................. Point A
G1 X15 Z65 ................................ Section A-B
Z55 .............................................. Section B-C
X40 Z30 ...................................... Section C-D
Z0 ................................................ Section D-E
G0 X50 Z100
M30
Incremental coordinates (G91)
G90 G95 G96 F0.15 S180 T2 D2 M4 M41
G0 X50 Z100
G1 X0 Z80 .................................. Point A
G1 G91 X15 Z-15 ...................... Section A-B
Z-10 ............................................ Section B-C
X25 Z-25 .................................... Section C-D
Z-30 ............................................ Section D-E
G0 G90 X50 Z100
M30
Programming in diameters
Absolute coordinates (G90)
G90 G95 G96 F0.15 S180 T2 D2 M4 M41
G0 X100 Z100
G1 X0 Z80 .................................. Point A
G1 X30 Z65 ................................ Section A-B
Z55 .............................................. Section B-C
X80 Z30 ...................................... Section C-D
Z0 ................................................ Section D-E
G0 X100 Z100
M30
Incremental coordinates (G91)
G90 G95 G96 F0.15 S180 T2 D2 M4 M41
G0 X100 Z100
G1 X0 Z80 .................................. Point A
G1 G91 X30 Z-15 ...................... Section A-B
Z-10 ............................................ Section B-C
X50 Z-25 .................................... Section C-D
Z-30 ............................................ Section D-E
G0 G90 X100 Z100
M30