Siemens SINUMERIK 840D sl Owner's manual

SINUMERIK
SINUMERIK 840D sl
Measuring cycles
Programming Manual
Valid for:
Control system
SINUMERIK 840D sl / 840DE sl
Software
CNC software Version 4.8 SP2
SINUMERIK Operate for PCU/PC version 4.8 SP2
12/2017
6FC5398-4BP40-6BA1
Preface
Fundamental safety
instructions 1
Description 2
Measuring variants 3
Parameter lists 4
Changes from cycle version
SW4.4 and higher A
Appendix B

Legal information
Warning notice system
This manual contains notices you have to observe in order to ensure your personal safety, as well as to prevent
damage to property. The notices referring to your personal safety are highlighted in the manual by a safety alert
symbol, notices referring only to property damage have no safety alert symbol. These notices shown below are
graded according to the degree of danger.
DANGER
indicates that death or severe personal injury will result if proper precautions are not taken.
WARNING
indicates that death or severe personal injury may result if proper precautions are not taken.
CAUTION
indicates that minor personal injury can result if proper precautions are not taken.
NOTICE
indicates that property damage can result if proper precautions are not taken.
If more than one degree of danger is present, the warning notice representing the highest degree of danger will be
used. A notice warning of injury to persons with a safety alert symbol may also include a warning relating to property
damage.
Qualified Personnel
The product/system described in this documentation may be operated only by personnel qualified for the specific
task in accordance with the relevant documentation, in particular its warning notices and safety instructions. Qualified
personnel are those who, based on their training and experience, are capable of identifying risks and avoiding
potential hazards when working with these products/systems.
Proper use of Siemens products
Note the following:
WARNING
Siemens products may only be used for the applications described in the catalog and in the relevant technical
documentation. If products and components from other manufacturers are used, these must be recommended or
approved by Siemens. Proper transport, storage, installation, assembly, commissioning, operation and
maintenance are required to ensure that the products operate safely and without any problems. The permissible
ambient conditions must be complied with. The information in the relevant documentation must be observed.
Trademarks
All names identified by ® are registered trademarks of Siemens AG. The remaining trademarks in this publication
may be trademarks whose use by third parties for their own purposes could violate the rights of the owner.
Disclaimer of Liability
We have reviewed the contents of this publication to ensure consistency with the hardware and software described.
Since variance cannot be precluded entirely, we cannot guarantee full consistency. However, the information in
this publication is reviewed regularly and any necessary corrections are included in subsequent editions.
Siemens AG
Division Digital Factory
Postfach 48 48
90026 NÜRNBERG
GERMANY
Document order number: 6FC5398-4BP40-6BA1
Ⓟ 11/2017 Subject to change
Copyright © Siemens AG 2006 - 2017.
All rights reserved

Preface
SINUMERIK documentation
The SINUMERIK documentation is organized into the following categories:
● General documentation/catalogs
● User documentation
● Manufacturer/service documentation
Additional information
You can find information on the following topics at the following address (https://
support.industry.siemens.com/cs/de/en/view/108464614):
● Ordering documentation/overview of documentation
● Additional links to download documents
● Using documentation online (find and search in manuals/information)
If you have any questions regarding the technical documentation (e.g. suggestions,
corrections), please send an e-mail to the following address
(mailto:[email protected]).
mySupport/Documentation
At the following address (https://support.industry.siemens.com/My/ww/en/documentation),
you can find information on how to create your own individual documentation based on
Siemens' content, and adapt it for your own machine documentation.
Training
At the following address (http://www.siemens.com/sitrain), you can find information about
SITRAIN (Siemens training on products, systems and solutions for automation and drives).
FAQs
You can find Frequently Asked Questions in the Service&Support pages under Product
Support (https://support.industry.siemens.com/cs/de/en/ps/faq).
SINUMERIK
You can find information about SINUMERIK at the following address (http://www.siemens.com/
sinumerik).
Measuring cycles
Programming Manual, 12/2017, 6FC5398-4BP40-6BA1 3

Target group
This programming manual is intended for machine tool programmers for the SINUMERIK
Operate software.
Benefits
With the programming manual, the target group can develop, write, test, and debug programs
and software user interfaces.
Standard scope
This documentation only describes the functionality of the standard version. Additions or
revisions made by the machine manufacturer are documented by the machine manufacturer.
Other functions not described in this documentation might be executable in the control. This
does not, however, represent an obligation to supply such functions with a new control or when
servicing.
For the sake of simplicity, this documentation does not contain all detailed information about
all types of the product and cannot cover every conceivable case of installation, operation, or
maintenance.
Technical Support
Country-specific telephone numbers for technical support are provided in the Internet at the
following address (https://support.industry.siemens.com/sc/ww/en/sc/2090) in the "Contact"
area.
Preface
Measuring cycles
4Programming Manual, 12/2017, 6FC5398-4BP40-6BA1

Table of contents
Preface.........................................................................................................................................................3
1Fundamental safety instructions...................................................................................................................9
1.1 General safety instructions.......................................................................................................9
1.2 Warranty and liability for application examples......................................................................10
1.3 Industrial security...................................................................................................................11
2 Description..................................................................................................................................................13
2.1 Basics.....................................................................................................................................13
2.2 General prerequisites.............................................................................................................15
2.3 Behavior on block search, dry run, program testing, simulation............................................16
2.4 Reference points on the machine and workpiece..................................................................18
2.5 Definition of the planes, tool types.........................................................................................20
2.6 Probes that can be used........................................................................................................23
2.7 Probe, calibration body, calibration tool.................................................................................27
2.7.1 Measuring workpieces on milling machines, machining centers............................................27
2.7.2 Measuring tools on milling machines, machining centers......................................................28
2.7.3 Measuring workpieces at the turning machines.....................................................................30
2.7.4 Measuring tools at lathes.......................................................................................................33
2.8 Measurement principle...........................................................................................................36
2.9 Measuring strategy for measuring workpieces with tool offset...............................................42
2.10 Parameters for checking the measurement result and offset.................................................45
2.11 Effect of empirical value, mean value, and tolerance parameters.........................................50
2.12 Tool offset strategy.................................................................................................................51
2.12.1 Correction strategy for tool offsets when measuring tools regarding tool groups
(replacement tools)................................................................................................................51
2.13 Measuring cycle help programs.............................................................................................52
2.13.1 CYCLE116: Calculation of center point and radius of a circle...............................................52
2.13.2 CYCLE119: Arithmetic cycle for determining position in space.............................................54
2.13.3 CUST_MEACYC: User program before/after measurements are performed........................56
2.14 Miscellaneous functions.........................................................................................................57
2.14.1 Measuring cycle support in the program editor......................................................................57
2.14.2 Measuring result screens.......................................................................................................57
2.14.3 Logging..................................................................................................................................60
2.14.3.1 General..................................................................................................................................60
2.14.3.2 Control cycle CYCLE150.......................................................................................................61
2.14.3.3 Log "Last measurement"........................................................................................................64
2.14.3.4 Standard log...........................................................................................................................65
2.14.3.5 User log..................................................................................................................................66
Measuring cycles
Programming Manual, 12/2017, 6FC5398-4BP40-6BA1 5

2.14.3.6 Displaying a user log in the form of a measurement results screen......................................70
2.14.3.7 Behavior during block search, simulation and for several channels......................................72
3 Measuring variants.....................................................................................................................................73
3.1 General requirements............................................................................................................73
3.1.1 Overview of the measuring cycles.........................................................................................73
3.1.2 Selection of the measuring variants via softkeys (turning).....................................................75
3.1.3 Selection of the measuring variants via softkeys (milling)......................................................78
3.1.4 Result parameters..................................................................................................................80
3.2 Measure workpiece (turning)..................................................................................................81
3.2.1 General information................................................................................................................81
3.2.2 Calibrate probe - length (CYCLE973)....................................................................................82
3.2.3 Calibrate probe - radius on surface (CYCLE973)..................................................................85
3.2.4 Calibrate probe - calibrate in groove (CYCLE973).................................................................88
3.2.5 Turning measurement - front edge (CYCLE974)...................................................................92
3.2.6 Turning measurement - inside diameter (CYCLE974, CYCLE994).......................................95
3.2.7 Turning measurement - outside diameter (CYCLE974, CYCLE994).....................................99
3.2.8 Extended measurement.......................................................................................................105
3.3 Measure workpiece (milling)................................................................................................107
3.3.1 General information..............................................................................................................107
3.3.2 Calibrate probe - length (CYCLE976)..................................................................................108
3.3.2.1 Function...............................................................................................................................108
3.3.2.2 Calling the measuring version..............................................................................................110
3.3.2.3 Parameters...........................................................................................................................110
3.3.2.4 Result parameters................................................................................................................112
3.3.3 Calibrate probe - radius in ring (CYCLE976).......................................................................112
3.3.4 Calibrate probe - radius on edge (CYCLE976)....................................................................117
3.3.5 Calibrate probe - radius between 2 edges (Cycle976).........................................................120
3.3.5.1 Function...............................................................................................................................120
3.3.5.2 Calling the measuring version..............................................................................................122
3.3.5.3 Result parameters................................................................................................................124
3.3.6 Calibrate probe - calibrate on ball (CYCLE976)...................................................................124
3.3.7 Edge distance - set edge (CYCLE978)...............................................................................128
3.3.8 Edge distance - align edge (CYCLE998).............................................................................134
3.3.9 Edge distance - groove (CYCLE977)...................................................................................141
3.3.10 Edge distance - rib (CYCLE977)..........................................................................................146
3.3.11 Corner - right-angled corner (CYCLE961)...........................................................................152
3.3.12 Corner - any corner (CYCLE961).........................................................................................157
3.3.13 Hole - rectangular pocket (CYCLE977)................................................................................163
3.3.14 Hole - 1 hole (CYCLE977)...................................................................................................168
3.3.15 Hole - inner circle segment (CYCLE979).............................................................................173
3.3.16 Spigot - rectangular spigot (CYCLE977)..............................................................................179
3.3.17 Spigot - 1 circular spigot (CYCLE977).................................................................................184
3.3.18 Spigot - outer circle segment (CYCLE979)..........................................................................190
3.3.19 3D - align plane (CYCLE998)...............................................................................................195
3.3.20 3D - sphere (CYCLE997).....................................................................................................200
3.3.21 3D - 3 spheres (CYCLE997)................................................................................................205
3.3.22 3D - angular deviation spindle (CYCLE995)........................................................................210
3.3.23 3D - kinematics (CYCLE996)...............................................................................................214
3.3.24 Expanded functionality CYCLE996......................................................................................232
3.3.24.1 Checking the sphere diameter.............................................................................................232
Table of contents
Measuring cycles
6Programming Manual, 12/2017, 6FC5398-4BP40-6BA1

3.3.24.2 Scaling of rotary axis vectors V1 and V2.............................................................................233
3.3.24.3 Compensation of the rotary axes orientation with VCS and CYCLE996..............................233
3.3.25 Measuring kinematics completely (CYCLE9960).................................................................234
3.3.25.1 Function...............................................................................................................................234
3.3.25.2 Mounting the calibration sphere...........................................................................................236
3.3.25.3 Measurement result display.................................................................................................239
3.3.25.4 Calibration on sphere...........................................................................................................241
3.3.25.5 Travel around the calibration sphere....................................................................................241
3.3.25.6 Tolerance limits....................................................................................................................242
3.3.25.7 Setting a fixed value (scaling)..............................................................................................242
3.3.25.8 Parameter............................................................................................................................243
3.3.26 3D measuring on machines with orientation transformation................................................246
3.3.27 Measuring with probe that cannot be positioned..................................................................247
3.3.27.1 Non-SPOS-capable spindle.................................................................................................247
3.3.27.2 Measuring probe permanently affixed to the machine.........................................................248
3.4 Measuring the workpiece on a machine with combined technologies.................................250
3.4.1 Measuring a workpiece on a milling/turning machine..........................................................250
3.4.2 Measuring a workpiece on a turning/milling machine..........................................................250
3.4.2.1 Allocating the trigger values.................................................................................................251
3.4.2.2 Uniformity when using a 3D probe of type 710....................................................................251
3.5 Measure tool (turning)..........................................................................................................253
3.5.1 General information..............................................................................................................253
3.5.2 Calibrate probe (CYCLE982)...............................................................................................255
3.5.3 Turning tool (CYCLE982).....................................................................................................261
3.5.4 Milling tool (CYCLE982).......................................................................................................265
3.5.5 Drill (CYCLE982)..................................................................................................................272
3.5.6 Measure tool with toolholder that can be orientated............................................................277
3.6 Measure tool (milling)...........................................................................................................279
3.6.1 General information..............................................................................................................279
3.6.2 Calibrate probe (CYCLE971)...............................................................................................281
3.6.3 Milling tool or drill (CYCLE971)............................................................................................287
3.6.3.1 Measurement with stationary spindle...................................................................................293
3.6.3.2 Measurement with rotating spindle......................................................................................293
3.6.3.3 Individually check teeth........................................................................................................295
3.6.3.4 Calling the measuring version milling tool............................................................................296
3.6.3.5 Calling the measuring version drill.......................................................................................297
3.6.3.6 Parameters...........................................................................................................................297
3.6.3.7 Result parameters................................................................................................................298
3.6.3.8 Measuring the tool on machines with combined technologies.............................................299
4 Parameter lists..........................................................................................................................................301
4.1 Overview of measuring cycle parameters............................................................................301
4.1.1 CYCLE973 measuring cycle parameters.............................................................................301
4.1.2 CYCLE974 measuring cycle parameters.............................................................................303
4.1.3 CYCLE994 measuring cycle parameters.............................................................................306
4.1.4 CYCLE976 measuring cycle parameters.............................................................................308
4.1.5 CYCLE978 measuring cycle parameters.............................................................................311
4.1.6 CYCLE998 measuring cycle parameters.............................................................................313
4.1.7 CYCLE977 measuring cycle parameters.............................................................................316
4.1.8 CYCLE961 measuring cycle parameters.............................................................................320
4.1.9 CYCLE979 measuring cycle parameters.............................................................................322
Table of contents
Measuring cycles
Programming Manual, 12/2017, 6FC5398-4BP40-6BA1 7

4.1.10 CYCLE997 measuring cycle parameters.............................................................................325
4.1.11 CYCLE995 measuring cycle parameters.............................................................................328
4.1.12 CYCLE996 measuring cycle parameters.............................................................................330
4.1.13 CYCLE982 measuring cycle parameters.............................................................................333
4.1.14 CYCLE971 measuring cycle parameters.............................................................................336
4.1.15 CYCLE150 measuring cycle parameters.............................................................................338
4.2 Additional parameters..........................................................................................................340
4.3 Additional result parameters................................................................................................342
4.4 Parameter............................................................................................................................343
A Changes from cycle version SW4.4 and higher.......................................................................................345
A.1 Assignment of the measuring cycle parameters to MEA_FUNCTION_MASK parameters....345
A.2 Changes in the machine and setting data from SW 4.4.......................................................348
A.3 Complete overview of the changed cycle machine and cycle setting data..........................349
A.4 Comparing GUD parameters (regarding measuring functions)............................................351
A.5 Changes to names of cycle programs and GUD modules...................................................355
B Appendix...................................................................................................................................................357
B.1 Abbreviations.......................................................................................................................357
B.2 Documentation overview......................................................................................................358
Glossary...................................................................................................................................................359
Index.........................................................................................................................................................365
Table of contents
Measuring cycles
8Programming Manual, 12/2017, 6FC5398-4BP40-6BA1

Fundamental safety instructions 1
1.1 General safety instructions
WARNING
Danger to life if the safety instructions and residual risks are not observed
If the safety instructions and residual risks in the associated hardware documentation are not
observed, accidents involving severe injuries or death can occur.
● Observe the safety instructions given in the hardware documentation.
● Consider the residual risks for the risk evaluation.
WARNING
Malfunctions of the machine as a result of incorrect or changed parameter settings
As a result of incorrect or changed parameterization, machines can malfunction, which in turn
can lead to injuries or death.
● Protect the parameterization (parameter assignments) against unauthorized access.
● Handle possible malfunctions by taking suitable measures, e.g. emergency stop or
emergency off.
Measuring cycles
Programming Manual, 12/2017, 6FC5398-4BP40-6BA1 9

1.2 Warranty and liability for application examples
The application examples are not binding and do not claim to be complete regarding
configuration, equipment or any eventuality which may arise. The application examples do not
represent specific customer solutions, but are only intended to provide support for typical tasks.
You are responsible for the proper operation of the described products. These application
examples do not relieve you of your responsibility for safe handling when using, installing,
operating and maintaining the equipment.
Fundamental safety instructions
1.2 Warranty and liability for application examples
Measuring cycles
10 Programming Manual, 12/2017, 6FC5398-4BP40-6BA1

1.3 Industrial security
Note
Industrial security
Siemens provides products and solutions with industrial security functions that support the
secure operation of plants, systems, machines and networks.
In order to protect plants, systems, machines and networks against cyber threats, it is
necessary to implement – and continuously maintain – a holistic, state-of-the-art industrial
security concept. Siemens products and solutions only represent one component of such a
concept.
The customer is responsible for preventing unauthorized access to its plants, systems,
machines and networks. Systems, machines and components should only be connected to
the enterprise network or the internet if and to the extent necessary and with appropriate
security measures (e.g. use of firewalls and network segmentation) in place.
Additionally, Siemens’ guidance on appropriate security measures should be taken into
account. For more information about industrial security, please visit:
Industrial security (http://www.siemens.com/industrialsecurity).
Siemens’ products and solutions undergo continuous development to make them more secure.
Siemens strongly recommends to apply product updates as soon as available and to always
use the latest product versions. Use of product versions that are no longer supported, and
failure to apply latest updates may increase customer’s exposure to cyber threats.
To stay informed about product updates, subscribe to the Siemens Industrial Security RSS
Feed at:
Industrial security (http://www.siemens.com/industrialsecurity).
WARNING
Unsafe operating states resulting from software manipulation
Software manipulations (e.g. viruses, trojans, malware or worms) can cause unsafe operating
states in your system that may lead to death, serious injury, and property damage.
● Keep the software up to date.
● Incorporate the automation and drive components into a holistic, state-of-the-art industrial
security concept for the installation or machine.
● Make sure that you include all installed products into the holistic industrial security concept.
● Protect files stored on exchangeable storage media from malicious software by with
suitable protection measures, e.g. virus scanners.
Fundamental safety instructions
1.3 Industrial security
Measuring cycles
Programming Manual, 12/2017, 6FC5398-4BP40-6BA1 11

Fundamental safety instructions
1.3 Industrial security
Measuring cycles
12 Programming Manual, 12/2017, 6FC5398-4BP40-6BA1

Description 2
2.1 Basics
General information
Measuring cycles are general subroutines designed to solve specific measurement tasks. They
can be adapted to specific problems via parameter settings.
When taking general measurements, a distinction is made between
●Tool measurement and
●Workpiece measurement.
Workpiece measurement
:=);
Workpiece measurement, turning example
=<;:
Workpiece measurement, milling example
In workpiece measurement, a probe is moved up to the clamped workpiece in the same way
as a tool and the measured values are acquired. The flexibility of measuring cycles makes it
possible to perform nearly all measurements required on a milling or turning machine.
The result of the workpiece measurement can be optionally used as follows:
● Compensation in the work offset
● Automatic tool offset
● Measurement without offset
Measuring cycles
Programming Manual, 12/2017, 6FC5398-4BP40-6BA1 13

Tool measurement
;=
Tool measurement, turning tool example
<=;
Tool measurement, drill example
In tool measurement, the selected tool is moved up to the probe and the measured values are
acquired. The probe is either in a fixed position or is swung into the working area with a
mechanism. The tool geometry measured is entered in the appropriate tool offset data set.
Description
2.1 Basics
Measuring cycles
14 Programming Manual, 12/2017, 6FC5398-4BP40-6BA1

2.2 General prerequisites
Certain preconditions must be met before measuring cycles can be used. These are described
in detail in the SINUMERIK 840D sl Base Software and Operating Software .
Check the preconditions using the following checklist:
●Machine
– All machine axes are designed in accordance with DIN 66217.
– Machine data has been adapted.
●Starting position
– The reference points have been approached.
– The starting position can be reached by linear interpolation without collision.
●Display functions of the measuring cycles
A HMI/PCU or HMI/TCU is required for showing the measuring result displays and for
measuring cycle support.
●Please observe the following when programming:
– Tool radius compensation is deselected before it is called (G40).
– The cycle is called no later than at the 5th program level.
– The measurement is also possible in a system of units that differs from the basic system
(with technology data that has been switched over).
For metric dimension system with active G70, G700.
For inch dimension system with active G71, G710.
References
Supplementary information for this documentation is provided in the following manuals:
● Commissioning Manual SINUMERIK 840D sl Base Software and Operating Software
– /IM9/ SINUMERIK Operate
● /PG/, Programming Manual SINUMERIK 840D sl / 828D Fundamentals
● /FB1/, Function Manual Basic Functions
● /FB2/, Function Manual Expanded Functions
● /FB3/, Function Manual Special Functions
Description
2.2 General prerequisites
Measuring cycles
Programming Manual, 12/2017, 6FC5398-4BP40-6BA1 15

2.3 Behavior on block search, dry run, program testing, simulation
Function
The measuring cycles are skipped during execution if one of the following execution modes is
active:
● "Trial run" ($P_DRYRUN=1)
● "Program test" ($P_ISTEST=1)
● "Block search" ($P_SEARCH=1),
only if $A_PROTO=0.
Simulation and simultaneous recording
Setting the measuring cycles under a simulated environment
Setting data SD55618 $SCS_MEA_SIM_ENABLE
= 0: The measuring cycles are exited without any function.
= 1: The measuring cycles are executed.
A distinction is made between the following simulation versions:
-Simulation in the HMI Operate editor
Traversing motion is visualized.
Measurement results and measurement result display are not available.
-SinuTrain
Measurement results and measurement result display are available.
Traversing motion can be visualized using the simultaneous recording function.
-For systems that exclusively operate with simulated axes (e.g. virtual machines,
NCU in a test rack application)
Measurement results and measurement result display are available.
Traversing motion can be visualized using the simultaneous recording function.
The following parameters should be observed for simulation in Sinutrain and
systems with simulated axes:
If MD13230 $MN_MEAS_PROBE_SOURCE = 1 to 8,
then set MD10360 $MN_FASTIO_DIG_NUM_OUTPUTS >= 1!
SD55619 $SCS_MEA_SIM_MEASURE_DIFF = input of simulated measure‐
ment difference
Measuring cycles and measurement results under a simulated environment (SinuTrain) are
used for programming for training purposes if a real machine is not available. The
measurement results also involve "simulated" values, which can also deviate from the setting
in MD13231 MEAS_PROBE_OFFSET, but which are influenced by these.
Description
2.3 Behavior on block search, dry run, program testing, simulation
Measuring cycles
16 Programming Manual, 12/2017, 6FC5398-4BP40-6BA1

Figure 2-1 Measuring - simulation
Description
2.3 Behavior on block search, dry run, program testing, simulation
Measuring cycles
Programming Manual, 12/2017, 6FC5398-4BP40-6BA1 17

2.4 Reference points on the machine and workpiece
General information
Depending on the measuring task, measured values may be required in the machine
coordinate system (MCS) or in the workpiece coordinate system (WCS).
For example: It may be easier to ascertain the tool length in the machine coordinate system.
Workpiece dimensions are measured in the workpiece coordinate system.
Where:
● M = machine zero in the machine coordinate system
● W = workpiece zero in the workpiece coordinate system
● F = tool reference point
Reference points
6SLQGOHFKXFN:RUNSLHFH19LQ=0==/)/:;;
=;=;/<:0)<
The position of tool reference point F in the machine coordinate system is defined with machine
zero M as the machine actual value.
The position of the tip/cutting edge of the active tool in the workpiece coordinate system is
displayed with the workpiece zero W as workpiece actual value. For a workpiece probe, the
center or the end of the probe ball can be defined as the tool tip.
The work offset (WO) characterizes the position of the workpiece zero W in the machine
coordinate system.
Work offsets (WO) comprise the components offset, rotation, mirroring and scaling factor (only
the global basic work offset does not contain any rotation).
A distinction is made between the basic, work offset (G54 ... G599) and programmable work
offset. The basic area contains further subsections – such as the basic work offset, channel-
specific basic work offset and configuration-dependent work offsets (e.g. rotary table reference
or basic reference).
Description
2.4 Reference points on the machine and workpiece
Measuring cycles
18 Programming Manual, 12/2017, 6FC5398-4BP40-6BA1

The specified work offsets are effective together as a chain and result in the workpiece
coordinate system.
For "Correction in a work offset", in conjunction with measuring cycles, a distinction is made
between two different cases.
Correction to the coarse offset:
An absolute offset value is determined between the machine zero and the measured
workpieces zero. This offset is written into the coarse component of the selected work offset
and deleted in the fine component.
Correction to the fine offset:
The measured difference is written as offset to the fine component of the selected work offset
and is added to the course component.
The input window work offset coarse/fine in the automatic measuring cycle screens is activated
using SD54760 $SNS_MEA_FUNCTION_MASK_PIECE, bit 10 = 1.
Note
Scale factors with a scaling value unequal to "1" are not supported by the measuring cycles!
Mirroring functions are only permitted in conjunction with counterspindles on turning machines.
The machine and workpiece coordinate system can be set and programmed separately in the
"inch" or "metric" measuring system.
Note
Transformation
● Measure workpiece
Workpiece measurements are always performed in the workpiece coordinate system. All
descriptions relating to workpiece measurement refer to it!
● Measure tool
When measuring tools with kinematic transformation active, a distinction is made between
basic coordinate system and machine coordinate system.
If kinematic transformation is deactivated, this distinction is made.
All subsequent descriptions relating to tool measurement assume that kinematic
transformation is disabled and therefore refer to the machine coordinate system.
Description
2.4 Reference points on the machine and workpiece
Measuring cycles
Programming Manual, 12/2017, 6FC5398-4BP40-6BA1 19

2.5 Definition of the planes, tool types
When measuring under milling, machining planes G17, G18 or G19 can be selected.
When measuring under turning, machining plane G18 must be selected.
For tool measurement, the following tool types are permitted:
● Milling, type 1..
● Drill, type 2 ...
● Turning tools, type 5 ...
For workpiece measurement, the following tool types are permitted:
● Workpiece probe, milling: Probe types 710, 712, 713, 714
● Workpiece probe, turning: Probe type 580 for turning machines without extended milling
technology, otherwise 710
See "Measuring the workpiece on a machine with combined technologies (Page 250)".
Milling
=<;
**
*
Depending on the tool type, the tool lengths are assigned to the axes as follows:
Acts in ... G17 plane G18 plane G19 plane
Tool type: 1xy / 2xy / 710
Length 1 1st axis of the plane: Z Y X
Length 2 2nd axis of the plane: Y X Z
Length 3 3rd axis of the plane: X Z Y
Description
2.5 Definition of the planes, tool types
Measuring cycles
20 Programming Manual, 12/2017, 6FC5398-4BP40-6BA1